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How to scale a part in SolidWorks

The Scale feature resizes model geometry by a factor. It is useful for 3D printing a model at a reduced size, for mould cavities and for data export.

Watch the video for the walkthrough. The written steps below follow the software publisher’s documentation, so menu names may differ slightly from the version in the video.

Scale a part

  1. In a part, click Scale on the Features toolbar, or go to Insert, Features, Scale.
  2. Under Scale About, choose Centroid, Origin or Coordinate System.
  3. Keep Uniform Scaling selected and enter a Scale Factor. Clear it to set separate X, Y and Z factors.
  4. Accept the feature.

Working out the factor

The factor multiplies each dimension. To print a real object at 1:50, use 1 ÷ 50 = 0.02. To convert a model drawn in the wrong units from inches to millimetres, use 25.4. The drawing scale converter will check the arithmetic.

Which point to scale about

Centroid keeps the part centred on its calculated centre. Origin keeps the origin fixed, which is usually what you want if the part must stay located in an assembly. Coordinate System uses one you have already defined. If material is on only one side of an axis, the model scales in only one direction along that axis.

The trap: dimensions do not change

The feature scales only the geometry. It does not scale dimensions, sketches or reference geometry. A drawing of the part can therefore show dimensions that do not match the scaled shape. If the design really is changing size, edit the dimensions instead.

To get back to full size, roll back or suppress the Scale feature.

Questions

Can I scale only some bodies?

Yes. In a multibody part, choose which solid or surface bodies to scale.

Can each configuration have its own scale?

Yes. Choose the configurations in the PropertyManager, or drive the factors from a design table.

Does scaling change wall thickness?

Yes. Walls and holes scale too, so a printed model at 0.02 can end up with walls too thin to print.

Related: drawing scale converter, batch export drawings to PDF.

Sources

Last checked 9 November 2026 against the documentation listed above. See the disclaimer.